1. Start Pro/E Wildfire.

2. Select [File] -> [New], and type the part name as [Benchvise100_part4].

3. Select the Extrude tool icon followed by the sketcher icon at the bottom of the screen.

4. Click on the reference plane labeled FRONT to select it as the sketch plane.

5. Click on the sketch button, and switch to sketch mode.

6. Draw the profile shown in Figure 1.1.

                                                                                                                        [Fig1.1]

7. Select the Continue icon from the tool bar to exit the Sketcher Mode.

8. Type 1.25 into the Extrusion Depth textbox on the dashboard to set the thickness of the part.

9. Click the green check button on the dashboard.

10. Select [View] -> [Orientation] -> [Default Orientation] from the menu bar.  You should see the part as shown in Figure 1.2.

                                                                                                                        [Fig 1.2]

11. Select the Extrude tool icon, followed by the Sketch icon.

12. Select the right surface of the part as the sketch plane, and the TOP face to be the reference plane, as shown in Figure 1.3.

                                                                                                                        [Fig 1.3]

13.Draw the profile shown in Figure 1.4. 

                                                                                                                        [Fig 1.4]

14. Select the Continue icon from the tool bar to exit the Sketcher Mode.

16. Select the Remove Material Icon, and specify the Depth Value to be 1.00. Make sure that the yellow arrow points in the correct direction; see Figure 1.5.

                                                                                                                        [Fig 1.5]

18. Click on the green check button to complete the extrusion of the cut.

19. Select the Hole Tool icon from the toolbar on the right, and as shown in Figure 1.6:

• Place it 0.50 units from the right surface of the part, and 1.88 units from the TOP plane.
• Input 0.25 in the Diameter textbox.
• Select the .Drill to Select Point, Curve, Plane or Surface icon in the Depth pull down menu, and select the triangular face of the cut to mark the end of the hole.

                                                                                                                        [Fig 1.6]

20. Click on the green check button to complete the hole execution.

21. Select [Edit] -> [Feature Operations]. From the Menu Manager:

Select [Copy] -> [Mirror] -> [Select] -> [Dependent] -> [Done]

• Select the cut and the hole (CTRL key might need ot be pressed to select both) that got completed in previous two steps, and click on [Done]; see Figure 1.7.
• Select [Setup Plane] -> [Plane], and choose the RIGHT plane on the model. Select [Done] from the menu manager.

                                                                                                                        [Fig 1.7]

22. The model, so far, should like Figure 1.8. 

                                                                                                                        [Fig 1.8]

23. Select the Hole Tool icon from the toolbar on the right, and as shown in Figure 1.9:

• Select the shaded plane (pink) to place the hole.
• Place it 0.125 units from the vertical and horizontal edges of the shaded area (pink).
• Input 0.125 in the Diameter textbox.
• Select the .Drill to Select Point, Curve, Plane or Surface icon in the Depth pull down menu, and select the edge of the other cut (opposite)  to mark the end of the hole.

                                                                                                                        [Fig 1.9]

24. Select the Hole Tool icon from the toolbar on the right, and as shown in Figure 1.10:

• Select the shaded plane (pink) to place the hole.
• Place it 0.00 units from the RIGHT plane, and 2.00 units from the TOP plane.
• Input 0.43755 in the Diameter textbox.
• Select the .Drill to Specific Depth icon in the Depth pull down menu, and type 0.50 in the Depth box to mark the end of the hole.

                                                                                                                         [Fig 1.10]

25. Click on the green check button to complete the hole.

26. The completed model should look like Figure 1.11.

                                                                                                                            [Fig 1.11]