Bench Vise Part 1

1. Start Pro/E Wildfire.

2. Select [File] -> [New], and type the part name as [Benchvise100_part1].

3. Select the Extrude tool icon followed by the sketcher icon at the bottom of the screen.

4. Click on the reference plane labeled FRONT to select it as the sketch plane.

5. Click on the sketch button, and switch to sketch mode.

6. Draw the profile as shown in Figure 1.1.

[Fig 1.1]

7. Select the Continue icon from the tool bar to exit the Sketcher Mode.

8. Type 3.00 into the Extrusion Depth textbox on the dashboard to set the thickness of the part.

9. Click the green check button on the dashboard.

10. Select [View] -> [Orientation] -> [Default Orientation] from the menu bar. You should see the part as shown in Figure 1.2.

[Fig 1.2]

11. Select the Extrude tool icon, followed by the Sketch icon.

12. Select the right surface of the part as the sketch plane, and the TOP face as the reference plane, as shown in Figure 1.3.

[Fig 1.3]

13.Draw the profile shown in Figure 1.4.

[Fig 1.4]

14. Select the Continue icon from the tool bar to exit the Sketcher Mode.

16. Select the Remove Material Icon, and specify the Depth Value to be 1.00. Make sure that the yellow arrow points away from the model.

18. Click on the green check button to complete the extrusion of the cut; the model should resemble Figure 1.5.

[Fig 1.5]

19. Select the Extrude tool icon, followed by the Sketch icon.

20. Select the TOP plane as the sketch plane, and the RIGHT plane as the reference plane.

21. Sketch the profile shown in Figure 1.6.

[Fig 1.6]

22. Select the Continue icon from the tool bar to exit the Sketcher Mode.

23. Set the Extrusion Depth Value to be 0.25; see Figure 1.7 for the completed protrusion.

[Fig 1.7]

24. Select the Hole Tool icon from the toolbar on the right, and as shown in Figure 1.8:

Select the shaded area (pink) to be the sketch plane.
Place it 1.00 units from the RIGHT plane, and 0.50 units from the diameter of the semicircle..
Input 0.25 in the Diameter textbox.
Select the Drill Up to Next Section icon in the Depth pull down menu.

[Fig 1.8]

25. Click on the green check button to complete the hole.

26. Select [Edit] -> [Feature Operations]. From the Menu Manager:

Select [Copy] -> [Move] -> [Select] -> [Dependent] -> [Done]
Select the Semicircular protrusion and the hole (CTRL key might need to be pressed to select both components) that got completed in previous two steps, and click on [Done].
Select [Translate] -> [Plane], and choose the RIGHT plane on the model. Make sure the red arrow points to the interior of the model, and select [Okay].
Enter offset distance to be 4.00, and click on the green check button; see Figure 1.9.
Select [Done Move]; no more offset distances need to be set.
Select [Okay] from the [Group Elements] menu.

[Fig 1.9]

27. Select the Make Datum icon from the right toolbar. For its references, click on the FRONT plane, and enter an offset distance of 1.50 towards the interior.

28. Select [OK] on the Datum Plane Menu to complete modeling of the new datum, DTM1 (your names could differ).

29. Select [Edit] -> [Feature Operations]. From the Menu Manager:

Select [Copy] -> [Mirror] -> [Select] -> [Dependent] -> [Done]
Select the semicircular protrusion, the hole and the copied group (CTRL key might need to be pressed to select them all) that got completed in previous three steps, and click on [Done].
Select [Setup Plane] -> [Plane], and choose the DTM1 plane, that was just created on the model. Select [Done] from the menu manager; the model should resemble Figure 1.10 below.

[Fig 1.10]

30. Select the Extrude tool icon, followed by the Sketch icon.

31. Select the shaded surface (pink) as the sketch plane, and the TOP plane as the reference plane; see Figure 1.11.

[Fig 1.11]

32. Sketch the profile shown in Figure 1.6.

[Fig 1.12]

33. Select the Continue icon from the tool bar to exit the Sketcher Mode.

34. Select the Remove Material Icon, and choose the Depth Until Next Surface option from the Depth pull down menu. Make sure that the yellow arrow points away from the model.

35. Click on the green check button to complete the extrusion of the cut; the model should resemble Figure 1.13.

[Fig 1.13]

36. Select the Hole Tool icon from the toolbar on the right, and as shown in Figure 1.14:

Select the shaded area (pink) to be the sketch plane.
Place it 0.50 units from the right edge, and 0.50 units from the top edge of the shaded area..
Input 0.25 in the Diameter textbox.
Select the .Drill Upto Next Section icon in the Depth pull down menu.

[Fig 1.14]

37. Select [Edit] -> [Feature Operations]. From the Menu Manager:

Select [Copy] -> [Mirror] -> [Select] -> [Dependent] -> [Done]
Select the hole that just got created, and click on [Done].
Select [SetUp Plane] -> [Plane], and choose the DTM1 plane. Select [Done] from the menu manager; the model should resemble Figure 1.15 below.

[Fig 1.15]

38. Select the Hole Tool icon from the toolbar on the right, and as shown in Figure 1.16:

Select the shaded area (pink) to be the sketch plane.
Place it 2.370 units from the TOP plane, and 1.50 units from the left edge (vertical) of the shaded area..
Input 0.43755 in the Diameter textbox.
Select the Drill To Selected Point, Curve or Surface icon in the Depth pull down menu, and select the other end of the triangular protrusion to mark its end.

[Fig 1.16]

39. Click on the green check check button to complete the hole for the model.

40. Select the Hole Tool icon from the toolbar on the right, and as shown in Figure 1.17:

Select the shaded area (pink) to be the sketch plane.
Place it 1.25 units from the TOP plane, and 1.50 units from the left edge (vertical) of the shaded area..
Input 0.625 in the Diameter textbox.
Select the Drill To Specific Depth icon in the Depth pull down menu, and enter a value of 1.00 in the Depth textbox. .

[Fig 1.17]

41. Click on the green check button to complete the execution of the hole.

42. Select the Extrude tool icon, followed by the Sketch icon.

43. Select the shaded surface (pink) as the sketch plane, and the TOP plane as the reference plane; see Figure 1.18.

[Fig 1.18]

44. Sketch the profile shown in Figure 1.19.

[Fig 1.19]

45. Select the Continue icon to exit from the sketcher mode,

46. Select the Remove Material Icon, and choose the Extrude by Specific Depth option from the Depth pull down menu, and enter a value of 0.88 in the Depth textbox.

47. Make sure that the yellow arrow (for Remove Material) points downwards, as shown in Figure 1.20.

[Fig 1.20]

48. Click on the green check button to complete the extrusion of the cut.

49. The final completed model should look like Figure 1.21.

[Fig 1.21]